Chip Load Calculator

Chip Load Calculator

Growing AI Skill PRO

Enter Calculation

Optional: the value from your tool manufacturer chart, used to suggest a feed rate.

Formula

Chip Load=Feed Rate (mm/min)RPM×Fluteswhere{Suggested Feed=Target Chip Load (mm)×RPM×FlutesFeed per Rev=Feed Rate (mm/min)RPMRatio=Chip LoadTarget Chip Load (mm)\begin{gathered} \text{Chip Load} = \frac{\text{Feed Rate (mm/min)}}{\text{RPM} \times \text{Flutes}} \\[1.5em] \text{where}\quad \left\{ \begin{aligned} \text{Suggested Feed} &= \text{Target Chip Load (mm)} \times \text{RPM} \times \text{Flutes} \\ \text{Feed per Rev} &= \dfrac{\text{Feed Rate (mm/min)}}{\text{RPM}} \\ \text{Ratio} &= \dfrac{\text{Chip Load}}{\text{Target Chip Load (mm)}} \end{aligned} \right. \end{gathered}
Usage stats

Advertisement

Results

Chip Load per Tooth
0.1
mm per tooth per revolution
Chip load (microns) 100
Feed per revolution (mm/rev) 0.2
Cutting edge engagements per minute 24,000
Feed rate for your target chip load (mm/min) 2,400
Actual / target chip load ratio 1
Your chip load is close to the target range. Verify chip appearance and listen for chatter, then fine-tune in small steps.

Report an error on this page

What is chip load?

Chip load (also called feed per tooth) is the thickness of material each cutting edge removes per revolution of the tool. It is the single most useful number in a feeds-and-speeds setup: it tells you whether each flute is taking a real bite or merely rubbing the workpiece. Too small a chip load generates heat and burnishes the surface instead of cutting it; too large a chip load deflects or snaps the cutter. This calculator works for router bits, end mills and face mills, in metric or imperial units, because the relationship is pure geometry and applies anywhere.

Top-down diagram of a two-flute end mill moving through a workpiece, with each flute cutting a crescent-shaped chip of thickness fz
Chip load (fz) is how far the tool moves forward into the material each time one flute cuts.

The formula explained

Each revolution presents \(Z\) cutting edges, and the spindle turns \(N\) times per minute, so the tool makes \(N \times Z\) edge engagements every minute. Dividing the distance travelled in that minute by the number of engagements gives the advance per edge:

$$CL = \frac{F}{N \times Z}$$

where \(CL\) = chip load per tooth, \(F\) = feed rate in mm/min or in/min, \(N\) = spindle speed in RPM, and \(Z\) = number of flutes. Keep the units consistent: a feed in mm/min gives a chip load in mm; a feed in in/min gives a chip load in inches.

Advertisement
Schematic of a cutter moving forward in four equal steps of fz that together add up to one feed per revolution, f
Feed per revolution equals chip load times the number of flutes. Multiply that by RPM to get the feed rate.

Worked example

A 2-flute 6 mm end mill runs at 12,000 RPM with a feed rate of 2,400 mm/min:

$$CL = \frac{2400}{12000 \times 2} = \frac{2400}{24000} = 0.10\,\text{mm}$$

That is 100 microns per tooth, a healthy value for aluminium with a 6 mm cutter. If the chart calls for 0.05 mm instead, invert the formula: \(F = 0.05 \times 12000 \times 2 = 1200\) mm/min.

How to use the calculator

Pick your unit system, then enter the programmed feed rate, the spindle speed you actually run, and the flute count stamped on the cutter. Add a target chip load from the manufacturer chart and the calculator returns the feed rate that hits it, plus a ratio comparing your current setup to that target.

Typical Chip Load Ranges by Material and Tool Diameter

Chip load (feed per tooth) scales with cutter diameter far more than most beginners expect: a 1.5 mm micro end mill and a 12 mm end mill in the same material differ by roughly an order of magnitude in safe feed per tooth, because the thin shank simply cannot carry the cutting force. The table below gives starting feed-per-tooth bands for four diameter groups, with mm/tooth and in/tooth side by side.

Material Tool type assumed 1–3 mm 3–6 mm (≈1/8") 6–12 mm (≈1/4") 12–20 mm (≈1/2")
Softwood (pine, fir) 2-flute upcut spiral router bit 0.05–0.15 mm
0.002–0.006 in
0.20–0.40 mm
0.008–0.016 in
0.40–0.60 mm
0.016–0.024 in
0.55–0.90 mm
0.022–0.035 in
Hardwood & plywood 2-flute upcut spiral router bit 0.04–0.12 mm
0.002–0.005 in
0.15–0.30 mm
0.006–0.012 in
0.25–0.45 mm
0.010–0.018 in
0.40–0.65 mm
0.016–0.026 in
MDF / particleboard 2-flute upcut spiral router bit 0.05–0.13 mm
0.002–0.005 in
0.18–0.33 mm
0.007–0.013 in
0.28–0.50 mm
0.011–0.020 in
0.45–0.70 mm
0.018–0.028 in
Acrylic & soft plastics 1- or 2-flute O-flute / upcut router bit 0.03–0.10 mm
0.001–0.004 in
0.10–0.20 mm
0.004–0.008 in
0.15–0.30 mm
0.006–0.012 in
0.25–0.40 mm
0.010–0.016 in
Aluminium (6061-type) 2–3 flute solid carbide end mill 0.010–0.030 mm
0.0004–0.0012 in
0.025–0.060 mm
0.001–0.0024 in
0.050–0.110 mm
0.002–0.004 in
0.100–0.200 mm
0.004–0.008 in
Brass & bronze 2–4 flute solid carbide end mill 0.010–0.025 mm
0.0004–0.001 in
0.020–0.050 mm
0.0008–0.002 in
0.040–0.090 mm
0.0016–0.0035 in
0.080–0.160 mm
0.003–0.006 in
Mild / low-alloy steel 4-flute solid carbide end mill 0.005–0.015 mm
0.0002–0.0006 in
0.013–0.030 mm
0.0005–0.0012 in
0.025–0.060 mm
0.001–0.0024 in
0.060–0.130 mm
0.0024–0.005 in
Stainless (300-series) 4–5 flute solid carbide end mill 0.005–0.013 mm
0.0002–0.0005 in
0.010–0.025 mm
0.0004–0.001 in
0.020–0.050 mm
0.0008–0.002 in
0.050–0.100 mm
0.002–0.004 in

How to use these bands

  1. Start low, in the bottom third of the band, especially on a light-frame hobby router or when the tool is held in a long collet extension or has a long flute length.
  2. Check the resulting feed rate against your machine. With \(\text{Feed} = \text{Chip Load} \times \text{RPM} \times \text{Flutes}\), a 6 mm 2-flute bit at 16,000 RPM and 4,000 mm/min gives a chip load of 0.125 mm per tooth — mid-band for hardwood, but far too aggressive for steel at the same diameter.
  3. These are slotting / moderate-engagement figures. At light radial engagement (trochoidal or adaptive toolpaths well under half the diameter) radial chip thinning means the programmed feed per tooth must be raised above the table value to keep the actual chip thickness in range — your CAM system normally applies that correction.
  4. Judge by the chips, not the number. Dust and a squealing cut mean the chip load is too low (rubbing, heat, premature edge wear); chatter, deflection or a broken tool means it is too high.

These values are starting points consistent with the shape of published tooling-manufacturer feeds-and-speeds data — for example Onsrud's router-tool charts for wood, plastics and non-ferrous metals, Harvey Tool / Helical micro and miniature end mill data, and Sandvik Coromant material-class recommendations for milling. They are deliberately conservative generic figures and are not a substitute for the data sheet of the tool in your spindle: the cutter maker's own recommendation, for that exact geometry, coating, flute count and depth of cut, always supersedes a general table like this one. Tooling catalogues also differ by region in the material groupings they use (ISO P/M/K/N/S/H classes in Europe, AISI/SAE designations in North America, JIS grades in Japan), so match the grade name on your stock to the grade in the chart you are reading.

Advertisement
Three chip types compared: a thin dusty chip from too low a chip load, a well-curled chip from the right chip load, and a thick chip with a broken tool from too high a chip load
Too low a chip load rubs and overheats the tool, too high a chip load can break it, and the right one gives clean curled chips.

Chip Load Unit Conversions

Chip load is quoted in millimetres per tooth in metric shops and in inches per tooth (IPT) in imperial ones, and tooling charts mix in microns and "thou" (thousandths of an inch). All of it comes from two exact factors:

$$1\ \text{in} = 25.4\ \text{mm} \qquad 1\ \text{mm} = \frac{1}{25.4}\ \text{in} \approx 0.03937\ \text{in}$$

  • mm/tooth → in/tooth: divide by 25.4 (or multiply by 0.03937).
  • in/tooth → mm/tooth: multiply by 25.4.
  • mm/tooth → microns (µm): multiply by 1000. So 0.08 mm/tooth = 80 µm/tooth.
  • in/tooth → thou: multiply by 1000, since 1 thou = 0.001 in. So 0.0035 in/tooth = 3.5 thou.
  • Feed rate: mm/min ÷ 25.4 = in/min; in/min × 25.4 = mm/min.

Common chip-load equivalents

mm/tooth Microns/tooth in/tooth (exact) in/tooth (rounded) Thou
0.025 mm 25 µm 0.000984 in 0.001 in 1 thou
0.05 mm 50 µm 0.001969 in 0.002 in 2 thou
0.10 mm 100 µm 0.003937 in 0.004 in 4 thou
0.25 mm 250 µm 0.009843 in 0.010 in 10 thou
0.50 mm 500 µm 0.019685 in 0.020 in 20 thou
0.0254 mm 25.4 µm 0.001 in 0.001 in 1 thou
0.127 mm 127 µm 0.005 in 0.005 in 5 thou
0.254 mm 254 µm 0.010 in 0.010 in 10 thou

The last three rows are the exact inch-based values; the first five are the round metric values most catalogues print. Note that "0.025 mm = 0.001 in" is a convenient approximation, not an identity — the exact equivalent of 1 thou is 0.0254 mm, a 1.6% difference that is irrelevant for feed setting but matters if you are converting a tolerance.

Feed per tooth, feed per revolution and feed rate

Three quantities describe the same motion at different scales. With \(f_z\) the feed per tooth (chip load), \(f_n\) the feed per revolution, \(n\) the spindle speed in RPM and \(z\) the flute count:

$$f_n = f_z \times z \qquad\text{and}\qquad v_f = f_z \times z \times n = f_n \times n$$

In imperial terms the same chain reads IPR = IPT × flutes and IPM = IPT × flutes × RPM. Rearranged, chip load is simply the feed rate divided by the number of tooth passes per minute:

$$f_z = \frac{v_f}{n \times z}$$

Worked conversion

A 12.7 mm (1/2") 2-flute upcut router bit runs at 18,000 RPM with a programmed feed of 14,400 mm/min. Working through the chain:

  1. Feed per revolution: \(f_n = 14{,}400 \div 18{,}000 = 0.80\ \text{mm/rev}\)
  2. Feed per tooth: \(f_z = 0.80 \div 2 = \) 0.40 mm per tooth
  3. In inches: \(0.40 \div 25.4 = 0.01575\ \text{in/tooth} \approx 15.7\ \text{thou}\), i.e. 400 µm/tooth
  4. Feed rate in imperial: \(14{,}400 \div 25.4 = 566.9\ \text{in/min}\)
  5. Check: \(0.01575 \times 2 \times 18{,}000 = 567\ \text{in/min}\) ✓

Switching the calculator's units selector performs these conversions for you, but it is worth doing one by hand: a chip load quoted as "0.016" is 0.016 in/tooth in an American catalogue and 0.016 mm/tooth in a European one — a 25-fold difference, and the single most common cause of a snapped end mill when copying numbers between charts.

FAQ

What chip load should I aim for? It depends on tool diameter and material. As a rough guide, small router bits under 3 mm often run 0.01-0.05 mm per tooth, while 6-12 mm cutters in wood or aluminium run 0.05-0.25 mm. Always start from the tool maker data sheet.

Does depth of cut change chip load? No. Depth and width of cut change chip thinning, cutting forces and material removal rate, but chip load per tooth comes only from feed, RPM and flute count.

Why do my chips look like dust? Dust means the chip load is far too low, usually from high RPM with a timid feed. Raise the feed rate or drop the spindle speed until chips form visible flakes that carry heat away.

Last updated:

Most popular in Industry-Specific

View all Industry-Specific calculators